High efficiency milling (HEM) uses a long axial depth of cut with a short radial step-over, run at high speed on a dynamic or trochoidal toolpath. Done right, it spreads wear along the whole flute, generates less heat and removes more metal. Done wrong, the tool rubs instead of cutting, and wears out fast.
The most common mistake is not raising the feed enough.
What is radial chip thinning?
When a tool cuts half its diameter or more, each tooth takes a chip about as thick as the programmed feed per tooth. When the radial step-over is small, the tooth enters the material at a shallow angle, and the chip it makes is thinner than the feed you programmed.
A chip that's too thin doesn't carry heat away and lets the edge rub. That's why HEM speeds & feeds charts say the feed per tooth must be adjusted with a Radial Chip Thinning Factor (RCTF).
The adjustment
For a radial width of cut (ae) less than half the tool diameter (D):
RCTF = 1 ÷ √(1 − (1 − 2 × ae ÷ D)²)
Multiply the chart's feed per tooth by the RCTF to get the feed to program.
| Radial width of cut (% of diameter) | Multiply feed per tooth by |
|---|---|
| 5% | 2.29 |
| 10% | 1.67 |
| 15% | 1.40 |
| 20% | 1.25 |
| 25% | 1.15 |
| 30% | 1.09 |
| 40% | 1.02 |
| 50% or more | 1.00 (no adjustment) |
Worked example
A 1/2" 5-flute Majac Mills HEM end mill in low carbon steel, at a 10% radial step-over:
- The HEM chart gives 350–900 SFM. Starting in the middle, 625 SFM works out to 4,775 RPM (625 × 3.82 ÷ 0.5).
- The chart's feed per tooth at 1/2" is 0.0040".
- At 10% radial, RCTF = 1.67, so program 0.0067" per tooth.
- Feed rate = 4,775 × 5 flutes × 0.0067 = about 159 IPM.
Without the adjustment you'd run about 95 IPM: the chips would be too thin, and you'd lose both tool life and cycle time.
Other HEM tips
- Climb mill. It's preferred over conventional milling.
- Ramp and plunge at about half the feed. Use full feed only once the tool is engaged in the side cut.
- Start in the middle of the chart, then step up. If the cut is stable and quiet, raise SFM and/or feed per tooth in 5–10% increments.
- Use chipbreakers on long axial cuts. Majac Mills HEM tools come with or without chipbreakers. Chipbreakers keep chips short, so they clear easily and don't get re-cut.
See the full HEM speeds & feeds chart, or find a Majac Mills HEM end mill.
Questions about your application? Our technicians are happy to help. Call +1 705 728 8665 or .